Download Programming and Operating Manual - Service, Support

N40 G01 X60 Z60 F0.25
N50 M2=70
Spindle switches to axis mode.
N60 X50 C180
Spindle(C axis) is traversed with linear interpolation synchronous
to X.
N70 Z20 SPOS=90
Spindle is positioned to 90 degrees.
N80 M30
Example 3: Drill cross holes in turned part
Cross holes are to be drilled in this turned part. The running spindle is stopped at zero degrees and then successively turned
through 90°, stopped and so on.
G0 X100 Z100
N110 S2=1000 M2=3
Switch on cross drilling attachment.
N120 SPOSA=DC(0)
Set main spindle to 0° immediately,
the program will advance to the next block straight away.
N125 G0 X34 Z-35
Switch on the drill while the spindle is taking up position.
N130 WAITS
Wait for the main spindle to reach its position.
N135 G1 G94 X10 F250
Feedrate in mm/min (G96 is suitable only for the multi-edge
turning tool and synchronous spindle, but not for power tools on
the cross slide.)
N140G0 X34
N145 SPOS=IC(90)
The spindle is positioned through 90° with read halt in a positive
direction.
N150 G1 X10
N155 G0 X34
N160 SPOS=AC(180)
The spindle is positioned at 180° relative to the spindle zero
point.
N165 G1 X10
N170 G0 X34
N175 SPOS=IC(90)
The spindle turns in a positive direction through 90° from the
absolute 180° position, ending up in the absolute 270° position.
N180 G1 X10
N185 G0 X50
M30
92
Programming and Operating Manual (Turning)
6FC5398-5DP10-0BA1, 08/2013